J
Jim Flanagan
Guest
Anyone have a reliable spice model for the LM35 temp sensor they would
want to share?
Thanks...
Jim
want to share?
Thanks...
Jim
C
Colin Seymour
Guest
On Fri, 22 Apr 2005 00:21:55 GMT, Jim Flanagan <jflan@tampabay.rr.com>
wrote:
depending on the temperature setting in SPICE.
It is suitable for Linear Technology Corporation SwitcherCAD.
There is no simulation of the LM35 power supply, or any detail of the
internal circuit (which you didn't mention, anyway).
*SPICE Simulation of National Semiconductor LM35 Precision Centigrade
Temperature Sensor
*
*
X1 1 LM35
*
..subckt LM35 Out
* Simulation of National Semiconductor LM35 Precision Centigrade
Temperature Sensor
* By Colin Seymour http://www.cjseymour.plus.com/
*
* Spec for LM35 connected as Full-Range Centigrade Temperature Sensor:
* Vout = +1500 mV at +150°C
* = +250 mV at +25°C
* = -550 mV at -55°C
*
* Current source I1 and resistor R0 create a voltage source
* with a linear temperature coefficient tc1
* controlled by the SPICE temperature
* R = R0 * (1. + dt * tc1)
* where R0 is the resistance at the nominal temperature
* dt is the difference between the resistor's temperature
* and the nominal temperature TNOM
* LM35 tempco = 0.01 V per degree C
I1 0 N001 1
R0 N001 0 1 tc1=0.01
*
* Current source I2 and resistor R1 create a similar voltage source
* with the same linear temperature coefficient, but the temperature
* is fixed at zero C, which is the reference temperature
* for the LM35
I2 0 N002 1
R1 N002 0 1 tc1=0.01 TEMP=0
*
* G1 and R2 subtract the reference voltage from the
* temperature dependent voltage to obtain a temperature
* dependent output with zero at the reference temperature
* for the LM35.
* The output impedance is set to 0.1 ohms to match the
* dynamic impedance of the LM35 for a 1mA load
G1 0 Out N001 N002 10
R2 Out 0 0.1
..ends
* Simulation commands to plot the operating point
* over a temperature range
..step temp -55 150 5
..OP
..print V(1)
..end
There are more details and downloadable files at:
http://www.cjseymour.plus.com/elec/tempsens/tempsens.htm
wrote:
This model will simulate the temperature dependent output of an LM35,
depending on the temperature setting in SPICE.
It is suitable for Linear Technology Corporation SwitcherCAD.
There is no simulation of the LM35 power supply, or any detail of the
internal circuit (which you didn't mention, anyway).
*SPICE Simulation of National Semiconductor LM35 Precision Centigrade
Temperature Sensor
*
*
X1 1 LM35
*
..subckt LM35 Out
* Simulation of National Semiconductor LM35 Precision Centigrade
Temperature Sensor
* By Colin Seymour http://www.cjseymour.plus.com/
*
* Spec for LM35 connected as Full-Range Centigrade Temperature Sensor:
* Vout = +1500 mV at +150°C
* = +250 mV at +25°C
* = -550 mV at -55°C
*
* Current source I1 and resistor R0 create a voltage source
* with a linear temperature coefficient tc1
* controlled by the SPICE temperature
* R = R0 * (1. + dt * tc1)
* where R0 is the resistance at the nominal temperature
* dt is the difference between the resistor's temperature
* and the nominal temperature TNOM
* LM35 tempco = 0.01 V per degree C
I1 0 N001 1
R0 N001 0 1 tc1=0.01
*
* Current source I2 and resistor R1 create a similar voltage source
* with the same linear temperature coefficient, but the temperature
* is fixed at zero C, which is the reference temperature
* for the LM35
I2 0 N002 1
R1 N002 0 1 tc1=0.01 TEMP=0
*
* G1 and R2 subtract the reference voltage from the
* temperature dependent voltage to obtain a temperature
* dependent output with zero at the reference temperature
* for the LM35.
* The output impedance is set to 0.1 ohms to match the
* dynamic impedance of the LM35 for a 1mA load
G1 0 Out N001 N002 10
R2 Out 0 0.1
..ends
* Simulation commands to plot the operating point
* over a temperature range
..step temp -55 150 5
..OP
..print V(1)
..end
There are more details and downloadable files at:
http://www.cjseymour.plus.com/elec/tempsens/tempsens.htm
J
Jim Thompson
Guest
On Fri, 22 Apr 2005 00:21:55 GMT, Jim Flanagan <jflan@tampabay.rr.com>
wrote:
If you just want the mathematical equivalent just use a behavioral
voltage source:
Etemp node1 node2 Value = {(TEMP-273)*10m}
in PSpice, other "Spices" may use "B" sources and/or possibly use '..'
instead of {..} for expression delimiting.
...Jim Thompson
--
| James E.Thompson, P.E. | mens |
| Analog Innovations, Inc. | et |
| Analog/Mixed-Signal ASIC's and Discrete Systems | manus |
| Phoenix, Arizona Voice
480)460-2350 | |
| E-mail Address at Website Fax480)460-2142 | Brass Rat |
| http://www.analog-innovations.com | 1962 |
I love to cook with wine. Sometimes I even put it in the food.
wrote:
Colin posted one way.
If you just want the mathematical equivalent just use a behavioral
voltage source:
Etemp node1 node2 Value = {(TEMP-273)*10m}
in PSpice, other "Spices" may use "B" sources and/or possibly use '..'
instead of {..} for expression delimiting.
...Jim Thompson
--
| James E.Thompson, P.E. | mens |
| Analog Innovations, Inc. | et |
| Analog/Mixed-Signal ASIC's and Discrete Systems | manus |
| Phoenix, Arizona Voice
480)460-2350 | || E-mail Address at Website Fax
480)460-2142 | Brass Rat || http://www.analog-innovations.com | 1962 |
I love to cook with wine. Sometimes I even put it in the food.
N
nyffeler
Guest
In article <DsX9e.8682$716.8189@tornado.tampabay.rr.com>, Jim Flanagan <jflan@tampabay.rr.com> wrote:
http://www.cjseymour.plus.com/elec/tempsens/tempsens.htm
but don't know how accurate this model is.
recently I found one on
http://www.cjseymour.plus.com/elec/tempsens/tempsens.htm
but don't know how accurate this model is.
J
Jim Thompson
Guest
On Tue, 26 Apr 2005 06:15:12 GMT, nyffeler@phys.chem.ethz.ch
(nyffeler) wrote:
...Jim Thompson
--
| James E.Thompson, P.E. | mens |
| Analog Innovations, Inc. | et |
| Analog/Mixed-Signal ASIC's and Discrete Systems | manus |
| Phoenix, Arizona Voice480)460-2350 | |
| E-mail Address at Website Fax480)460-2142 | Brass Rat |
| http://www.analog-innovations.com | 1962 |
I love to cook with wine. Sometimes I even put it in the food.
(nyffeler) wrote:
Duh! That's Colin's that he posted here on 4/24 ;-)
...Jim Thompson
--
| James E.Thompson, P.E. | mens |
| Analog Innovations, Inc. | et |
| Analog/Mixed-Signal ASIC's and Discrete Systems | manus |
| Phoenix, Arizona Voice
480)460-2350 | || E-mail Address at Website Fax
480)460-2142 | Brass Rat || http://www.analog-innovations.com | 1962 |
I love to cook with wine. Sometimes I even put it in the food.