How to assign netnames through enterpath() function ?

  • Thread starter manu.saketdham@gmail.com
  • Start date
M

manu.saketdham@gmail.com

Guest
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.

I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.

Regards,
Kevin
 
manu.saketdham@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.

I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.

Regards,
Kevin
Click to expand...
Hi,
How about using option ?netName from your rodCreatePath() ?

Best Regards,
I-FAB
 
Hi,

I am able to assign the net names to with rodcreatepath. My questions
are:

1. Can i assign net names through "enterpath" function. If yes, HOW ?

2. How to assign MULTIPLE net names through rodcreatepath function? I
can assign names to Master path and the other paths through the offset
connectvity function. What if the number of paths are more.. eg: 50.
How to assign them the names!!!

Kevin

I-F AB wrote:
manu.saketdham@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.

I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.

Regards,
Kevin

Hi,
How about using option ?netName from your rodCreatePath() ?

Best Regards,
I-FAB
Click to expand...
 
manu.saketdham@gmail.com wrote, on 03/20/09 04:04:
Hi,

I am able to assign the net names to with rodcreatepath. My questions
are:

1. Can i assign net names through "enterpath" function. If yes, HOW ?

2. How to assign MULTIPLE net names through rodcreatepath function? I
can assign names to Master path and the other paths through the offset
connectvity function. What if the number of paths are more.. eg: 50.
How to assign them the names!!!

Kevin

I-F AB wrote:
manu.saketdham@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.

I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.

Regards,
Kevin
Hi,
How about using option ?netName from your rodCreatePath() ?

Best Regards,
I-FAB
Click to expand...
Here's an example, of adding ?netName in all the sub paths as well as the
master. I updated an old example I created 10 years ago ;->

/* abCreateBus.il

Author A.D.Beckett
Group Custom IC (UK), Cadence Design Systems Ltd.
Language SKILL
Date Mar 30, 1999
Modified Mar 20, 2009
By A.D.Beckett

An example of creating a bus using ROD.

The points could of course be specified by something like enterPath()
in practice.

Mar 20, 2009. Added new optional busPrefix to allow wires the be
on named nets.

***************************************************

SCCS Info: @(#) abCreateBus.il 03/20/09.12:59:54 1.2

*/

/******************************************************************
* *
* abCreateBus(cv layer points numWires [busPrefix]) *
* *
* Create a bus with given points, in the specified cellView, with *
* the specified number of wires. *
* *
******************************************************************/

procedure( abCreateBus(cv layer points numWires @optional busPrefix)
let( (tfId layerWidth layerSpace offsetPaths)
/* get technology file information */
tfId = techGetTechFile(cv)
layerWidth = techGetSpacingRule(tfId "minWidth" layer)
layerSpace = techGetSpacingRule(tfId "minSpacing" layer)
/* construct the list of sub paths */
for(bit 1 numWires-1
offsetPaths=tconc(offsetPaths
list(
?netName when(busPrefix sprintf(nil "%s<%d>" busPrefix bit))
?layer layer
?justification "left"
?sep layerSpace*bit + layerWidth*(bit-1)
)
)
)
rodCreatePath(
; ?name "bus"
?netName when(busPrefix sprintf(nil "%s<0>" busPrefix))
?layer layer
?pts points
?width layerWidth
?justification "center"
?cvId cv
?offsetSubPath car(offsetPaths)
)
); let
);
 
eric.d.fitzsimmons@gmail.com wrote, on 03/20/09 12:52:
On Mar 19, 11:04 pm, "manu.saketd...@gmail.com"
manu.saketd...@gmail.com> wrote:
Hi,

I am able to assign the net names to with rodcreatepath. My questions
are:

1. Can i assign net names through "enterpath" function. If yes, HOW ?

2. How to assign MULTIPLE net names through rodcreatepath function? I
can assign names to Master path and the other paths through the offset
connectvity function. What if the number of paths are more.. eg: 50.
How to assign them the names!!!

Kevin



I-F AB wrote:
manu.saketd...@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.
I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.
Regards,
Kevin
Hi,
How about using option ?netName from your rodCreatePath() ?
Best Regards,
I-FAB- Hide quoted text -
- Show quoted text -

All,

I don't have an answer, but I am interested in the solution as
well.

Another problem we have were I work is we have GaAS process where the
engineering is done on different schematic software, so there isn't
any way to have the layout "schematic driven". It is a mess.
There is NO connectivity the way these designs were layed out, no pins
on child cells, no net names. The only pins are on the pad out.
Layout by brail.

On the other hand, these designs are not very complex. Maybe 30 or
so nets in the design. It would be nice to start assigning net names
to the wires and tagging the instances the same as schematic and
placing text on the instances. The layout is done by a cumbersome
method of looking at a text file that defines connectivity and tracing
each net and using LVS for debug. Yuck.

So my question, how can you add a net name to an Existing wire that
was made with creat path? I see you can draw a wire with Create Path
with a Net Name. Can a net be assigned retro fit?

Thank you in advance,
Eric
Click to expand...
Eric,

Use the Connectivity->Add Shape to Net form. You may want to uncheck the "Auto"
button so you can type in the net name you want.

Regards,

Andrew.
 
On Mar 19, 11:04 pm, "manu.saketd...@gmail.com"
<manu.saketd...@gmail.com> wrote:
Hi,

I am able to assign the net names to with rodcreatepath. My questions
are:

1. Can i assign net names through "enterpath" function. If yes, HOW ?

2. How to assign MULTIPLE net names through rodcreatepath function? I
can assign names to Master path and the other paths through the offset
connectvity function. What if the number of paths are more.. eg: 50.
How to assign them the names!!!

Kevin



I-F AB wrote:
manu.saketd...@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i  assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.

I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.

Regards,
Kevin

Hi,
How about using option   ?netName   from your   rodCreatePath()  ?

Best Regards,
I-FAB- Hide quoted text -

- Show quoted text -
Click to expand...
All,

I don't have an answer, but I am interested in the solution as
well.

Another problem we have were I work is we have GaAS process where the
engineering is done on different schematic software, so there isn't
any way to have the layout "schematic driven". It is a mess.
There is NO connectivity the way these designs were layed out, no pins
on child cells, no net names. The only pins are on the pad out.
Layout by brail.

On the other hand, these designs are not very complex. Maybe 30 or
so nets in the design. It would be nice to start assigning net names
to the wires and tagging the instances the same as schematic and
placing text on the instances. The layout is done by a cumbersome
method of looking at a text file that defines connectivity and tracing
each net and using LVS for debug. Yuck.

So my question, how can you add a net name to an Existing wire that
was made with creat path? I see you can draw a wire with Create Path
with a Net Name. Can a net be assigned retro fit?

Thank you in advance,
Eric
 
On Mar 20, 8:15 am, Andrew Beckett <andr...@DcEaLdEeTnEcTe.HcIoSm>
wrote:
eric.d.fitzsimm...@gmail.com wrote, on 03/20/09 12:52:





On Mar 19, 11:04 pm, "manu.saketd...@gmail.com"
manu.saketd...@gmail.com> wrote:
Hi,

I am able to assign the net names to with rodcreatepath. My questions
are:

1. Can i assign net names through "enterpath" function. If yes, HOW ?

2. How to assign MULTIPLE net names through rodcreatepath function? I
can assign names to Master path and the other paths through the offset
connectvity function. What if the number of paths are more.. eg: 50.
How to assign them the names!!!

Kevin

I-F AB wrote:
manu.saketd...@gmail.com wrote:
I have used rodcreatepath and able to assign the net names by the
offset connectivity option. If i suppose to have 50 paths, its a tough
ask to pass values to all 50 nets. For eg: i  assign net_1 to the
master path, then the sub-paths automatically assign the names
net_2,net_3... net_50 for the remaining 49 sub-nets.
I am able to draw multipaths with the help of enterpath function, but
couldn't pass the net names through it. Can anyone tell me what i need
to add in the enterpath function to get the net names assigned through
it.
Regards,
Kevin
Hi,
How about using option   ?netName   from your   rodCreatePath()  ?
Best Regards,
I-FAB- Hide quoted text -
- Show quoted text -

All,

I don't have an answer, but I am interested in the solution as
well.

Another problem we have were I work is we have GaAS process where the
engineering is done on different schematic software, so there isn't
any way to have the layout "schematic driven".    It is a mess.
There is NO connectivity the way these designs were layed out, no pins
on child cells, no net names.  The only pins are on the pad out.
Layout by brail.

On the other hand, these designs are not very complex.   Maybe 30 or
so nets in the design.   It would be nice to start assigning net names
to the wires and tagging the instances the same as schematic and
placing text on the instances.  The layout is done by a cumbersome
method of looking at a text file that defines connectivity and tracing
each net and using LVS for debug.  Yuck.

So my question, how can you add a net name to an Existing wire that
was made with creat path?   I see you can draw a wire with Create Path
with a Net Name.   Can a net be assigned retro fit?

Thank you in advance,
Eric

Eric,

Use the Connectivity->Add Shape to Net form. You may want to uncheck the "Auto"
button so you can type in the net name you want.

Regards,

Andrew.- Hide quoted text -

- Show quoted text -
Click to expand...
Andrew,

I have some more questions.

I was able to attach a net to an existing wire that had no
connectivity only if the net existed. Can I add a net that doesn't
exist to the design?

Can I change the net assignment? How does that work? This could
happen if the engineer changes scematic(remember we have some layout
that originates from an unsupported scematic source, at least that is
my understanding so schematic driven doesn't work.)

Are these assignments permanent, meaning can I save the file in the
library and when I bring it back up the net will be there?

Thank you in advance,
Eric
 
eric.d.fitzsimmons@gmail.com wrote, on 03/20/09 15:49:
Andrew,

I have some more questions.

I was able to attach a net to an existing wire that had no
connectivity only if the net existed. Can I add a net that doesn't
exist to the design?
Click to expand...
Hi Eric,

Looks as if you have to create the net first. Either add a shape and define the
net as you add the shape, or do:

dbCreateNet(geGetEditCellView() "albert") ; albert is the net name

in the CIW, and then add the shape to the net.

Can I change the net assignment? How does that work? This could
happen if the engineer changes scematic(remember we have some layout
that originates from an unsupported scematic source, at least that is
my understanding so schematic driven doesn't work.)
Click to expand...
Changing the net assignment is a bit more awkward - you'd have to delete all the
shapes from the net and then add them again to the new net.

Alternatively you might need to run in Layout XL without a schematic source, and
then overlapping shapes should inherit the nets. There is a special property
that gets added when you create a shape with a net name called "lxStickyNet"
(set to true) which means that that shape's net name is "sticky" - when you
short it to other "sticky" nets you'll get connectivity errors.

Are these assignments permanent, meaning can I save the file in the
library and when I bring it back up the net will be there?
Click to expand...
Yes, they're permanent.

Thank you in advance,
Eric
Click to expand...
Regards,

Andrew.
 
I implemented the same concept in my code. I am able to generate
netnames for the sub-parts. When i select the properties of the master-
path, it shows the mentioned spacing and width in the sub-part tab.
Everything seems to work fine. In the layout canvas,all the sub-nets
are overlapped on the master path. i.e. Only master path is drawn,
rest all sub-nets are overlapping the master path. Can anyone tell me,
what Wrong I am doing?

Andrew Beckett wrote:
eric.d.fitzsimmons@gmail.com wrote, on 03/20/09 15:49:
Andrew,

I have some more questions.

I was able to attach a net to an existing wire that had no
connectivity only if the net existed. Can I add a net that doesn't
exist to the design?

Hi Eric,

Looks as if you have to create the net first. Either add a shape and define the
net as you add the shape, or do:

dbCreateNet(geGetEditCellView() "albert") ; albert is the net name

in the CIW, and then add the shape to the net.


Can I change the net assignment? How does that work? This could
happen if the engineer changes scematic(remember we have some layout
that originates from an unsupported scematic source, at least that is
my understanding so schematic driven doesn't work.)

Changing the net assignment is a bit more awkward - you'd have to delete all the
shapes from the net and then add them again to the new net.

Alternatively you might need to run in Layout XL without a schematic source, and
then overlapping shapes should inherit the nets. There is a special property
that gets added when you create a shape with a net name called "lxStickyNet"
(set to true) which means that that shape's net name is "sticky" - when you
short it to other "sticky" nets you'll get connectivity errors.


Are these assignments permanent, meaning can I save the file in the
library and when I bring it back up the net will be there?


Yes, they're permanent.

Thank you in advance,
Eric

Regards,

Andrew.
Click to expand...
 
manu.saketdham@gmail.com wrote, on 03/24/09 06:24:
I implemented the same concept in my code. I am able to generate
netnames for the sub-parts. When i select the properties of the master-
path, it shows the mentioned spacing and width in the sub-part tab.
Everything seems to work fine. In the layout canvas,all the sub-nets
are overlapped on the master path. i.e. Only master path is drawn,
rest all sub-nets are overlapping the master path. Can anyone tell me,
what Wrong I am doing?
Click to expand...
If (with my ESP circuit enabled) you used ?encSubPath to create these sub-paths,
then they will all have the same definition line as the master path, so that
wouldn't be surprising. If you used ?offsetSubPath to create the sub-paths, then
you probably didn't specify ?sep to specify the separation of the sub-path's
centre line to the master line.

Of course, my Extra-Sensory Perception circuit may be faulty, so if this doesn't
explain it, you might actually want to show the part of your code which is
having the problem?

Regards,

Andrew.
 
You must log in or register to reply here.

Welcome to EDABoard.com

Sponsor

Back
Top